EAGLE Central Forums
Where the EAGLE community meets. Sponsored by Stratford Digital.

Home » CadSoft Support Forums » eagle.suggest.eng » Change netname by wiring to copied Xref label
Change netname by wiring to copied Xref label [message #167961] Fri, 02 December 2016 03:09 Go to next message
Steve Parus
Messages: 4
Registered: December 2016
Junior Member
To make a connection between multiple pins for example without drawing a wired net, their netnames can be given the same name.  Once the first netname is assigned, each of the other names must be manually changed by editing the name.  It would be quicker and not require typing if the copy of a netname label as Xref could be directly wired to the other desired pins or connections.  Or just moved to the termination of an existing wire and the connection automatically made.  There probably should be a popup requesting confirmation of changing the netname, similar to what happens now if a netname if changed manually by typing and editing a new name.

Is this feasible or can it already be accomplished somehow?

Steve

--
To view any images and attachments in this post, visit:
https://www.element14.com/community/message/210470
Re: Change netname by wiring to copied Xref label [message #167962 is a reply to message #167961] Fri, 02 December 2016 07:12 Go to previous messageGo to next message
Lorenz
Messages: 650
Registered: December 2006
Senior Member
Steve Parus wrote:
> To make a connection between multiple pins for example without drawing
> a wired net, their netnames can be given the same name.  Once the
> first netname is assigned, each of the other names must be manually
> changed by editing the name.  It would be quicker and not require
> typing if the copy of a netname label as Xref could be directly wired
> to the other desired pins or connections.  Or just moved to the
> termination of an existing wire and the connection automatically
> made.  There probably should be a popup requesting confirmation of
> changing the netname, similar to what happens now if a netname if
> changed manually by typing and editing a new name.

1) draw the first net stub and attach the label.
2) group the label and the end of the net stub it is connected to
3) copy & paste as needed.

the duplicates keep the net name and can be used to start other net
segments.

You can do this even for multiple nets at once.


Be aware that placing the free end of such a copy on a pin won't
connect.
You will need to pick up the part and drop it in place to make the
connection. But no need to do that for each single net, you can do it
once after you have placed all nets for that part.

--

Lorenz
Re: Change netname by wiring to copied Xref label [message #167971 is a reply to message #167961] Fri, 02 December 2016 14:43 Go to previous messageGo to next message
Ed Robledo
Messages: 49
Registered: August 2005
Member
On 12/01/2016 10:09 PM, Steve Parus wrote:
> To make a connection between multiple pins for example without drawing a wired net, their netnames can be given the same name. Once the first netname is assigned, each of the other names must be manually changed by editing the name. It would be quicker and not require typing if the copy of a netname label as Xref could be directly wired to the other desired pins or connections. Or just moved to the termination of an existing wire and the connection automatically made. There probably should be a popup requesting confirmation of changing the netname, similar to what happens now if a netname if changed manually by typing and editing a new name.
>
> Is this feasible or can it already be accomplished somehow?
>
> Steve
>
> --
> To view any images and attachments in this post, visit:
> https://www.element14.com/community/message/210470
>

Hi Steve,
Another option is to use Buses. Type the command 'BUS' and draw your bus
within the schematic. Using the context menu on the bus select the NAME
command and name your bus with as many names you think you will be
needing. For example, DB[1..7],A[0..7],RST,IN .... and press OK. With
the NET command active click on the bus. All names will become
available to select. I hope the attachments helps.
I hope this helps.
Regards,
Ed
  • Attachment: bus.png
    (Size: 10.69KB, Downloaded 140 times)
Re: Change netname by wiring to copied Xref label [message #167974 is a reply to message #167962] Fri, 02 December 2016 15:16 Go to previous messageGo to next message
Steve Parus
Messages: 4
Registered: December 2016
Junior Member
Thanks Lorenz.
The trick is to have a net wire connected to the netname label Xref and then group and copy both.  If only the label is copied, then a line is drawn from it back to its origin net as it is moved around, indicating I suppose that it is associated/locked to that net..
I too observe that if the grouped label and net wire stub is initially moved such that the end of the stub contacts a pin, that connection is not actually made.  That can be observed by moving the pin or its component-there is no connection.  But moving the pin back so it contacts the end of the stub does result in the connection being made.  Alternatively, the initial placement can be made without contacting the pin and then the pin or its component moved so they do connect.
Steve

--
To view any images and attachments in this post, visit:
https://www.element14.com/community/message/210517
Re: Change netname by wiring to copied Xref label [message #167982 is a reply to message #167961] Sun, 04 December 2016 07:22 Go to previous message
warrenbrayshaw
Messages: 1767
Registered: January 2010
Location: New Zealand
Senior Member
On 2/12/2016 4:09 p.m., Steve Parus wrote:
> To make a connection between multiple pins for example without drawing a wired net, their netnames can be given the same name. Once the first netname is assigned, each of the other names must be manually changed by editing the name. It would be quicker and not require typing if the copy of a netname label as Xref could be directly wired to the other desired pins or connections. Or just moved to the termination of an existing wire and the connection automatically made. There probably should be a popup requesting confirmation of changing the netname, similar to what happens now if a netname if changed manually by typing and editing a new name.
>
> Is this feasible or can it already be accomplished somehow?
>
> Steve
>
> --
> To view any images and attachments in this post, visit:
> https://www.element14.com/community/message/210470
>

Since a number of suggestions are appearing here (Not quite what the
suggest forum is for) here is another approach.

Enter in the command line, 'Net' and the name of the net you would like
all over the place. Let's call it CLK

NET CLK <enter>
Place the first net and 'escape ' to end the net segment.
Press the up arrow to display the NET CLK command again in the command
line and hit <enter>
Place the second net of the same name CLK
Repeat as many times as necessary.
Maybe you would like to label the net as you go.
For a regular label on the net you have just placed, you could right
click on the net and select 'label' from the context menu and place a
label. Then continue with more nets as before using the up arrow to get
back your initial command.

Should you want XREF labels, rather than changing to an xref using teh
label's properties, I would enter into the command line LABEL XREF
<enter> and place an xref label directly.

Now you have two command preloaded in the command line so use multiple
up arrows to get the particular one you need.

The nets are named with the desired name as you place them rather than
going back and renaming them later.

HTH
Warren
Previous Topic: Origin layer at schematic editor
Next Topic: How do I Export a png file for silkscreen when a file does not show up and export to clipboard does not produce a file to be found in Freeware version on Windows Xp computer?
Goto Forum:
  


Current Time: Tue Sep 19 22:21:15 GMT 2017